Versions 1.6.6 to 1.6.8 shorten the path from source data to a finished program. You load a turned part from a STEP file, insert a DIN 509 undercut into the contour with one click, and CAM Turning machines it straight away. The simulator also executes Siemens 840D variables and expressions, and the G-code comparison shows changes far more clearly.
DIN 509 undercuts: inserting into a DXF contour
An undercut next to a cylinder and face is often not drawn in CAD, or the drawing shows only a sharp corner. In the Misc → DIN groove menu you open the DIN 509 undercut window, choose an undercut from the profile previews and click the inner corner of the contour between the cylinder and the face. The corner becomes the undercut's zero, the profile is inserted and the cylinder and face lines are trimmed to its end points. Undo reverts the insertion.
The library contains 26 undercuts:
- F (F0.4, F0.6, F1.0, F1.6): the undercut stays within the cylinder and does not cut into the face.
- FW (FW0.4, FW0.6, FW1.0): angled cut into the face.
- FL (FL0.4, FL0.6, FL1.0): long variant of form F.
- FP (FP0.4): cut into the face.
- E: 12 sizes from E0.2x0.1 to E4x0.5 according to the DIN 509 table.
- G (G0.4x0.2): cut into the face, flank angle 17.5°, according to the DIN 509 table.
- H (H0.8x0.3, H1.2x0.3): cut into the face, flank angle 15°, according to the DIN 509 table.
Rounded corner. If the contour has a radius in the corner, click the intersection of the two sides as if the radius were not there. A snap point Intersection with an X mark appears at that spot. The radius is replaced by the undercut. It must be a tangential 90° arc.
Machining DIN 509 undercuts in CAM Turning
CAM recognises the DIN undercut from the geometry, not from the template name, so it also works for undercuts drawn in CAD. Roughing and semi-finishing run along the sharp corner, with the cylinder and face extended to their intersection, so the groove does not interrupt them. The undercut itself is machined according to its type:
- Undercut cutting into the face (FW, FP, G, H): a separate pass after finishing, from below or from above.
- Undercut not cutting into the face (F, FL, E): no separate pass. The final pass runs directly along the undercut. With No dragging enabled it runs from behind and cuts the undercut from above.
The Groove & finishing tab, shown only for contours with an undercut, has two more options:
- Pre-roughing with allowance: the same pass offset by the allowance (max. 2 mm) runs at roughing feed before the finished pass.
- Do not machine the undercut: everything runs along the sharp corner, the undercut is skipped and no warnings appear.
Reach check. The program verifies that the insert and holder fit into the undercut and that the nose radius is smaller than the undercut radius. If the tool would cut in, the undercut is not machined, stays sharp, and a warning says by how many millimetres and where. Tests show that F and FL can be handled by most tools except 80° inserts (CNMG). FW and FP require a tool with a sufficiently relieved front edge: in the tested set that was a 35° V insert in a 117.5° holder, while holders with Kr 91–95° cut in.
The cut starts and ends outside the material, and on the diameter the tool exits 0.05 mm above the finished diameter so that it is not machined repeatedly. The workpiece and stock in the simulation both show the undercut cavity in the face.
Limitations: currently outer diameter, Z direction and G40 only. Internal undercuts and G41/G42 are not supported. The reach of the insert and holder is checked, not the whole holder body.
Help cards in the CAM window
When you hold the cursor over an option for 0.5 seconds, a card with an illustration and explanation appears. The cards cover No dragging, angled entry, semi-finishing, rest stock, finishing direction and all DIN undercut options. You can find out what the options mean without the manual.
STEP import: a 2D profile from a 3D model
The CAD import panel (formerly DXF Overlay) also loads .stp and .step files through the Import DXF / STEP… button. A turned part becomes a 2D profile, outer and optionally inner. From there you work with it like an ordinary DXF contour: set the zero, offset or Z mirror and use it in CAM. The face is part of the profile, so the contour is continuous.
The rotation axis is found automatically. If there are several axes, you switch between them in the Rotation axis list and the profile is recalculated.
Siemens 840D: variables, expressions and frames
The simulator now executes what it used to ignore and runs line by line, so loops using IF … GOTOB work too:
- Variables:
DEF REAL/INT/BOOL, R parametersR0…R299and custom names. - Expressions in axis words: for example
X=R1+2,Z=-R2*SIN(30),F=R5,X=IC(R1). - Conditional jumps:
IF cond GOTOF/GOTOB label, when GOTO jump simulation is enabled in the machine configuration. - Frames:
TRANS/ATRANS,SCALE/ASCALE,MIRROR/AMIRROR,ROT/AROT.
Reworked G-code comparison
The Compare G-code dialog has a list of changes with Previous change and Next change buttons. A jump zooms both canvases and scrolls the text to that spot. The canvases share zoom and pan, and the toolpath display switches between All paths, Dim unchanged and Changes only. The Ignore N-numbers option is available, and counters show how many lines were added, removed and modified.
Grooves in CAM: angled walls, necks and face grooves
- Angled groove walls are roughed in levels in CAM Grooving instead of converging diagonals, and the Z allowance is kept at the wall.
- Nested grooves respect the minimum groove width.
- A neck behind a shoulder is roughed like a groove on the RMPX ramp.
- Unreachable corners are checked against the real contour, and the
Set min widthbutton sets the minimum width with one click. - The contour preview marks in red what will not be machined as drawn.
- Face (axial) grooves are followed by CAM only when both insert and holder fit into the contour. Finishing also handles a steep far flank and contours with a reversed Z direction.
- The nose radius follows the selected insert, so you do not need to overwrite it manually.
- The collision check switches automatically between estimated stock and stock from DXF.
Opening programs from Windows and a new installer
Double-clicking a program (.nc, .tap, .mpf, .cnc, .spf, .min, .gcode, .ngc, .din, .pgm, .pbd and more) opens it directly in MultiPath. Drag & drop works the same way. The application runs as a single instance, so another file goes to the window that is already open. The new installer sets up these associations and installs for the current user, without administrator rights.
Other improvements
- The Setup Sheet is saved with the project: header fields, tool edits, manual and hidden rows, PDF options, columns and cost report inputs.
- The grooving tool label is split into holder, insert and radius columns in the Setup Sheet.
- The
Tooltoggle in the simulation hides or shows the holder with the insert. .mpcncprojects can be opened by drag & drop, and each remembers its own view.- Tool Catalog: new GARANT MTJNR 93 holders (2020K16, 2525M16, 2525M22, 3232P22) and T 3232 in size 22.